Review Oct 30, 2026 · 7 min read

Makera Z1 Pro in Steel: Every Problem I Hit (and My Feeds and Speeds)

I milled a C45 steel part on the Makera Z1 Pro over six evenings. My feeds and speeds, every problem I hit, and how accurate the part came out.

The vise of my manual mill weighs more than this whole machine. So when a desktop CNC like the Makera Z1 Pro says it can do metal, I want to see it in steel. Not for five minutes, but for a whole part.

This post goes with the full video on YouTube. It has my feeds and speeds in a table you can copy, every problem I ran into, and what I did about each one.

Makera supplied this Z1 Pro and saw the video before release. They didn’t pay for it and asked for no changes. The tests and conclusions are mine.

My Makera Z1 Pro feeds and speeds for C45 steel

These are the settings I ended up with after six evenings: C45 steel, air blast, spindle at 13,000 rpm, carbide end mills.

CutToolFeedEngagement
Bore, helix down4 mm 4F carbide400 mm/min3 mm helix, 0.04 mm/rev
Bore, spiral out4 mm 4F carbide2,600 mm/min0.05 mm deep, 4 mm wide
Top face4 mm 4F carbide2,600 mm/min0.05 mm deep, 3.8 mm wide
Finish passes4 mm 4F carbide2,000 mm/min1 mm pitch helix, 0.1 mm radial
Back face6 mm 4F carbide2,600 mm/min0.06 mm deep, 3.5 mm wide
Chamfers6 mm 90° 2F carbide300 mm/min0.2 mm, then 0.3 mm
C45 steel, air blast, spindle at 13,000 rpm. From my CAM programs; I ran the feed override between 80 and 200%.

At 13,000 rpm with four flutes, 2,600 mm/min is 0.05 mm per tooth. The cut is shallow but almost as wide as the end mill. That’s not ideal for tool life, because you only use the tip of the end mill. On a light machine it gives a much smoother cut.

My rule: find the maximum first, then back off about 20%. That’s where the results get good.

One more tip: before a cut like this, I restart the program a few lines back so it eases into the material. Start in the wrong spot and a 0.1 mm cut suddenly becomes 0.5 mm.

What Makera recommends instead

I asked Makera about the heat. Their advice for steel: 11,000 rpm and 1,000 mm/min. That’s less than half my feed rate, so the same toolpath takes more than twice as long.

Makera advice for steel on the Z1 Pro: 11,000 rpm and 1,000 mm/min, versus 13,000 rpm and 2,600 mm/min that I ran

If you want the machine to run cool and don’t mind waiting, start there. I’m not making money with this machine, but my time is still worth something.

The test part

The part is a block of C45 steel: 74 by 74 mm, 12 mm thick, with a big bore in the middle. Boring and side milling let me compare deep, narrow cuts with wide, shallow ones. Then a second setup to take 7 mm off the back.

Short runs are easy. I wanted to see how the Z1 Pro holds up over hours of cutting, and what goes wrong after that.

Every problem I hit

The bore and the helix angle

The bore was the hardest part. I started with a 1.5 degree helix and ended at 0.25 degrees. The steeper the helix, the more it bites on every turn, and on a light machine that’s one of the hardest cuts. I still don’t know which angle is best.

My settings mistake

I simulate my cuts in Millalyzer, which shows the cutting force on the end mill. Around 10 newtons is my sweet spot, and the graph looked nice and stable.

Then the cut started to whine. I had swapped cutting depth and cutting width in my settings, so it was cutting way too hard. The graph was right, my settings were wrong. A cut narrower than the end mill makes the force keep swinging, and this machine has no mass to damp it.

The fix was a new strategy: almost the full width of the end mill and much less depth. That’s what’s in the table above.

Chips inside the machine

On the second evening the spindle kept overheating. After some googling, clogging seemed to be a known issue, and when I looked, mine had way more chips inside than I expected. Steel chips are like little needles. Cleaning them out is part of running steel on this machine.

Spindle heat

Heat was the real limit. While taking 7 mm off the back, the spindle temperature kept climbing towards 75°C. At 75°C it stops, and then you reset and probe everything again.

What I tried: the fan at 100%, the feed override down to 80%, and the vacuum on for more airflow. The vacuum actually made it warmer. What worked: pause, let it cool with the fan at max, go back to my old cut parameters and back off the feed.

I was only removing about 1 cm³ per minute. You can go much slower, but then a part like this takes a day, and this isn’t a machine you leave alone for eight hours. I think the pre-production Z1 handled heat better. The Pro is easy to overheat.

Probing a crooked vise

Something on my vise was crooked, so the part was too. My own probing app, which drives the probe through Makera Studio, has a Reference Plane feature: it probes the tilt and builds a height map to compensate. This was the first time I used it on a real part.

Y axis motor error

The axis motors are closed loop. If they lose position, the machine stops the job. Mine stopped with a Y axis motor error and wanted a reset. After a reset you have to probe again, because you don’t know if everything is still where it should be. I restarted it and after that it was fine. I don’t know what caused it.

The probe died

On the last evening, while probing the bore, the Makera 3D probe died. No light, no signal, and the machine didn’t know. It drove the probe into the part. I had no spare, so the part is still not quite finished.

Makera 3D probe in the bore of the C45 steel part on the Z1 Pro

That clip became a Short with nearly 3 million views across YouTube, TikTok and Facebook. Most comments said user error. Mine had done about 300 probing cycles, and this time it just didn’t trigger.

Makera told me the firmware doesn’t check yet whether the probe still works, and that a fix is coming. They’re sending me a new probe. The whole story is in my post about the dead probe.

Until that fix is out: trigger the probe by hand before every probing routine and check that the machine sees it.

Chips in the linear guides

After the part, I looked under the covers. Black oil mixed with fine metal dust on the linear guides, and plenty of chips hanging on them. The chips are too heavy to get carried away. If you run steel, plan on cleaning.

How accurate is the part?

In the machine, my probe measured the outside at 74.01 by 74.01 mm. With calipers on the finished part: 73.95 to 74.00 mm on a 74 mm target, and about 0.1 mm off on the 12 mm thickness. No calibration, no wear compensation. For a machine like this, with these settings, that’s plenty good.

The bore is hard to measure properly with calipers. Next time I’d probe it on the machine.

The finish: the bore is very smooth, the outside faces are nicer than the top because I ran a finer finishing pass there, and the chamfers came out clean. On the top face you can feel the passes with a fingernail.

So, can the Makera Z1 Pro cut steel?

Yes. It works great, especially for finishing, even in steel. I pushed it hard on purpose to find where it stops.

It’s slow and heat is the limit, so plan for long jobs, chip cleaning and a few resets. Whether it’s worth the money is the next video. Before this one, I opened up a pre-production Z1 to see what’s inside.

What I used

🔥 Makera Z1 / Z1 Pro: see today’s price →

FAQ


On C45 I ended up at 13,000 rpm with a 4 mm four-flute carbide end mill at 2,600 mm/min, 0.05 mm deep and almost the full width of the end mill. Makera itself recommends 11,000 rpm and 1,000 mm/min. Find your maximum first, then back off about 20%.

In my test the spindle temperature kept climbing during long cuts, and the spindle stops at 75°C. Chips inside the machine made it worse. The fan at 100%, a lower feed and pauses to cool down kept it running. Turning on the vacuum made it warmer.

My C45 part came out within about 0.1 mm on the outside and the thickness, without calibration or wear compensation.

This part took about four hours of cutting, spread over six evenings. At Makera’s recommended settings the same toolpaths would take more than twice as long.

Got questions about steel on the Z1 Pro, or want my probing app? Join the Discord and let’s talk shop.

desktop cnc metalworking

Have questions about this build?

Join the Discord and let's talk shop.

forum Join the Discord

Related Posts

Gweike M3 Ultra vs xTool MetalFab: Specs, Cutting & Value Compared (2026)

Gweike M3 Ultra vs xTool MetalFab: Specs, Cutting & Value Compared (2026)

Jul 10, 2026
Gweike B25 vs Langmuir Titan 25T: Same Idea, Built Properly?

Gweike B25 vs Langmuir Titan 25T: Same Idea, Built Properly?

Nov 13, 2026
Affordable Chinese Granite Parallels — Are They Worth It? Mightymill

Affordable Chinese Granite Parallels — Are They Worth It?

May 9, 2023